# Running Ocellaris¶

## Running a simulation¶

Ocellaris is typically run from the command line with the name of an input file as the first argument:

ocellaris taylor-green.inp


You can optionally override parameters given on the input file:

ocellaris taylor-green.inp \
--set-input time/dt=0.1 \
--set-input 'solver/velocity_function_space="CG"'


You can see a summary of the command line options by running:

ocellaris --help


Ocellaris will normally create a log file with the information that is also shown on screen. This will contain a listing of the input after modification by the --set-input command line flag so that you can be sure to know exactly what you did run when you look back on an old simulation.

## Running a simulation on multiple CPUS with MPI¶

The procedure for running in parallel with MPI is different depending on whether you are running on an HPC (high performance cluster/computer), or on a single machine. On a cluster—where you can run Ocellaris in parallel across many machines—the method of running will also depend on whether your cluster has FEniCS or Singularity installed. One of these must be installed for Ocellaris to work.

Not on HPC

If you want to run in parallel on a single machine, then you will need to specify the number of parallel processes to the mpirun command, and it will launch and handle the parallel simulation. This also works inside a Singularity or Docker container. To run on 8 CPUs:

mpirun -np 8 ocellaris INPUTFILE.inp


You can see the number of CPUs that are being used in the Ocellaris log file to verify that it is working as intended. The log file will also show the number of mesh cells and function space unknowns per CPU.

FEniCS installed on HPC

If you have an installation of FEniCS at your local HPC cluster, and this version of FEniCS is compiled for your clusters favourite MPI implementation, then you can run Ocellaris just like any other MPI software (with the correct mpirun for the selected MPI implementation):

# In a job-script for SLURM, Grid Engine, etc.
mpirun ocellaris INPUTFILE.inp


The mpirun command (may also be called other names, check with your HPC documentation) will typically figure out how many CPUs you have been allocated, you normally do not have to specify this in the arguments to mpirun. You must typically write the above command inside a job-script and ask the HPC scheduler to run the script for you with a given number of CPUs. How you write the job-script and how you give it to the scheduler depends on your local HPC machine, and should be documented by the HPC administrators.

You can also use the orun.py script to babysit your simulation and make sure it is restarted if the cluster has a problem and the simulation freezes (this can unfortunately happen with complex parallel file system/MPI/Infiniband problems that are typically outside your control). You replace the call to mpirun with python3 orun.py .... The orun script currently only supports SLURM, but it is relatively easy to extend it to other schedulers. Send us a patch if you do!

Singularity installed on HPC

If you want to run on an HPC system where you do not have FEniCS available, but you do have Singularity, then you can use an MPICH ABI compatible mpirun from outside Singularity to launch your job:

# With a scheduler
mpirun singularity run ocellaris.img INPUTFILE.inp

# Without a scheduler
mpirun -np 16 singularity run ocellaris.img INPUTFILE.inp


You will need to use an MPICH ABI compatible mpirun, such as Intel MPI or MVAPICH2. You will probably also need to modify the Singularity image file so that you include the appropriate Infiniband drivers. As an example, see this description or this email for inspiration. By using a compatible MPI inside and outside the container it should be just as fast as a local install (from other people’s tests). This has not been tested on Ocellaris simulations, let us know if you have some data on this! Ocellaris is built with the standard MPICH library since this is what is used by the FEniCS Docker images that we use as a basis.

Talk to your local HPC admin to figure out which libraries are necessary to install inside the Singularity container. They may already have documents on using Singularity if they have installed in on the HPC system. We cannot document the exact steps to get it running here as HPC documentation is unfortunately still very system specific. Hopefully tools like Singularity and the push for reproducible science will improve this situation over time.

## Restart files¶

Ocellaris will by default save a restart file at the end of each simulation, named something like SIMNAME_endpoint_00000XYZ.h5. You can also configure Ocellaris to write restart files at given intervals or supply a user code that writes a restart file when given criteria are met. The restart file contains the input file that was used along with a very detailed log and all active fields (velocity, pressure, density etc).

If you need to restart from the end of a simulation, for example to run a bit further in time in case you set tmax a bit too short you can easily do this by:

ocellaris RESTART_FILE.h5 --set-input time/tmax=30.0


You will probably want to use --set-input since it is inconvenient (but certainly doable if you really want) to change the input description inside the restart file.

If you want you can inspect the contents of a restart file, which is stored on HDF5 format, by use of the graphical program HDFView, or command line applications like h5ls and friends, see HDF5 for more info. This is a relatively easy way to find out the exact input file that was used, read the detailed log etc. There are no known programs that can plot the fields inside a FEniCS DOLFIN HDF5 restart file (which is what Ocellaris uses).

## Graphical user interface¶

Preprocessing: There are many programs that can generate simplical 2D or 3D meshes that are compatible with Ocellaris. All mesh formats supported by meshio, can be read by Ocellaris. A rather good free graphical user interface for mesh generation is gmsh. The latest version (>3) has CAD capabilities and is used for several of the Ocellaris demos.

Postprocessing: Ocellaris can save results in XDMF format. There are several programs that can postprocess such files. Paraview is one good option. A custom post-processor, Ocellaris Inspector, also exist. It can be used to plot residuals and other time series produced by the simulator. The inspector is useful when Ocellaris is running (for plotting log files) and after finishing (plotting restart h5 files). All numbers printed on the screen and in the log file when Ocellaris is running should be accessible in the Ocellaris Inspector program.

## Controlling a running simulation¶

If you run Ocellaris directly from a command line prompt on one CPU (very unlikely) then you can type in the below commands directly. This is the reason for the short command lines, to enable quick and dirty use during debugging of the Ocellaris code on small toy examples.

If you are running Ocellaris in a cluster queue system and/or using MPI and hence have no access to the interactive console of the root process you can give commands in a command file. If your output prefix is such that the log file is called mysim.log then the name of the command file is mysim.COMMANDS. This file will not be created, you must make a new one every time. Ocellaris will read the file to check for commands and then DELETE the file to avoid running commands multiple times. The contained commands are processed at the end of the current time step. Each command should be on a separate line in the file.

d

Start a debug console - only use this when running interactively on 1 CPU!

f

Flush open files to disk (this is done periodically, but can be forced)

p

Plot field variables (legacy, avoid this).

r

Write restart file

s

Stop the simulation, changes input value time/tmax to the current time.

t

Show timings (shows the table normally shown at the end of a simulation)

i a/b/c = 12.3

Change the input file variable a/b/b to the value 12.3. The value will be evaluated as a Python expression.

w FORMAT

Write current simulation state to 3D visuamization output file of the given FORMAT (must be one of vtk or xdmf).

prof N

Run the Python profiler for the next N time steps and then print the resulting profiling information. This is good for figuring out which routine is tanking longer than expected if the timing information from the t command is not sufficient to understand the problem. Normally the PETSc Krylov solvers should take the majority of the time, but if not some profiling may be necessary. Note: this profiles the Python code only, the C++ code will not show any details on which part is taking time.

Example: the following COMMAND file will save a restart file, plot fields to XDMF and then stop the simulation:

r
w xdmf
s


You can run something like this to easily create the COMMAND file:

echo r > mysim.COMMANDS
echo "w xdmf" >> mysim.COMMANDS
echo s >> mysim.COMMANDS